Comparing 2D and 3D Structural Analysis - PowerPoint PPT Presentation

About This Presentation
Title:

Comparing 2D and 3D Structural Analysis

Description:

Workshop 4.2 Comparing 2D and 3D Structural Analysis Workshop 4.2 - Goals Workshop 4.1 consists of a 2 part assembly representing a pressure cap and retaining flange ... – PowerPoint PPT presentation

Number of Views:137
Avg rating:3.0/5.0
Slides: 35
Provided by: Sheld73
Learn more at: https://www-eng.lbl.gov
Category:

less

Transcript and Presenter's Notes

Title: Comparing 2D and 3D Structural Analysis


1
Comparing 2D and 3D Structural Analysis
  • Workshop 4.2

2
Workshop 4.2 - Goals
  • Workshop 4.1 consists of a 2 part assembly
    representing a pressure cap and retaining flange
    (full model shown below).
  • We will solve the model in 2 ways, as a 90 degree
    symmetry sector and as a 2D axisymmetric model
    (shown on next page).
  • Our goal is to compare the 2 methods both for
    consistency and for economy.

3
Workshop 4.2 - Geometry
  • Shown here are the 3D sector model and the 2D
    axisymmetry model.

Pressure Cap
Retaining Ring
4
Workshop 4.2 - Assumptions
  • Assumptions
  • The retaining ring is fixed at its mounting
    holes.
  • The contact region between the parts is
    frictionless.
  • The base of the pressure cap is constrained using
    a compression only support.
  • Note due to the presence of the bolt holes the
    structure is not truly axisymmetric. Part of our
    goal is to determine the validity of the
    axisymmetric assumption in this case.

5
Workshop 4.2 - Start Page
  • From the launcher start Simulation.
  • When DS starts, close the Template menu by
    clicking the X in the corner of the window.

6
Workshop 4.2 Geometry Setup
  • Before importing the geometry highlight the
    Geometry branch and change the Analysis Type
    preference to 2D in the details.
  • Choose Geometry gt From File . . . and browse
    to the file Axisym_pressure_2D.x_t.

7
Workshop 4.2 Preprocessing
  • Set the working unit system to the metric mm
    system.
  • Units gt Metric (mm, Kg, MPa, C, s).
  • Highlight Parts 1 and 2 in the tree and rename
    Retaining Ring and Pressure Cap.
  • In the details for each part, change their
    Behavior to Axisymmetric.

2
3
8
Workshop 4.2 Preprocessing
  • From details for the Pressure Cap and import
    the material Stainless Steel.

4
9
Workshop 4.2 Contact
  • Highlight the Contact Region and notice the
    target contains a single edge. We will add a
    second edge to insure all possible contact is
    detected.

Additional target edge to be added (shown dashed)
10
Workshop 4.2 Contact
  1. Click in the Target field then select the 2
    edges of the pressure cap shown here.
  2. Apply the new selection.

5
Select Edges
6
Note if you have difficulty selecting the edges
of the Pressure Cap, use the hide feature to
hide the retaining ring during selection.
11
Workshop 4.2 Contact
  1. In the Contact Region detail change the Type to
    Frictionless.
  2. Highlight the Mesh branch, RMB and Preview
    Mesh (note the speed with which the 2D mesh is
    generated as well as the density).

8
12
Workshop 4.2 Environment
  1. Highlight the Environment branch.
  2. Select the 3 inside edges of the Pressure Cap.
  3. RMB gt Insert gt Structural gt Pressure.
  4. Set the pressure magnitude 0.1 MPa.

10
12
13
Workshop 4.2 Environment
  1. Highlight the bottom edge of the pressure cap.
  2. RMB gt Insert gt Compression Only Support.

14
13
14
Workshop 4.2 Environment
  1. Select the middle line on the top of the
    retaining ring.
  2. RMB gt Insert gt Fixed Support.

16
15
Remember, the axisymmetric assumption here is
that the retaining ring is a continuous solid.
Actually there are bolt holes around its
circumference. For this reason, when the model
was created in DesignModeler this separate line
was intentionally created to provide a location
to add our support.
15
Workshop 4.2 Solution
  • Highlight the Solution branch, RMB and insert
  • Stress gt Equivalent (von-Mises)
  • Deformation gt Total
  • Switch to body select mode, select the pressure
    cap and repeat steps 16 and 17.
  • Solve

19
Note, the last two results are now scoped to the
pressure cap. This will allow us to isolate its
response.
16
Workshop 4.2 Solution
  • OK the weak spring message.
  • Note due to the fact that the pressure cap is
    constrained using frictionless contact and a
    compression only support, weak springs are added
    to prevent rigid body motion.
  • Notes on axisymmetry
  • Notice that the model lies completely in X space
    with the Y axis as the axis of revolution. This
    is required for axisymmetry.
  • Axisymmetry assumes that the model is a complete
    360 degree model. For this reason no constraints
    in the X direction are required. The portion of
    the pressure load acting in the X direction is
    assumed to be offset by an equal portion in the
    X direction.

17
Workshop 4.2 Postprocessing
  • Highlight each of the result objects to inspect
    the response.
  • Note due to meshing and machine variations,
    results may not match exactly those shown here.
  • For future reference, highlight the Equivalent
    Stress 2 result (scoped) and note the maximum
    value here________________

18
Workshop 4.2 Postprocessing
  • Highlight the Solution branch, RMB gt Insert gt
    Solution Information gt Solution Information.

The graphics window will change to the Worksheet
view. Scroll to the bottom of the solution
information and note the Elapsed Time (this will
vary by machine). Elapsed Time
___________________________ Note, CP time
represents the sum for all processors used. In
multiprocessor machines it will generally exceed
elapsed time.
19
Workshop 4.2 3D Symmetry Model
  • Close the current project (you may save the
    current 2D Simulation if desired).
  • Well now set up and solve the 3D symmetry model
    using the same boundary conditions.

20
Workshop 4.2 - Start Page
  • From the launcher start Simulation.
  • When DS starts, close the Template menu by
    clicking the X in the corner of the window.

21
Workshop 4.2 Geometry Setup
  • Choose Geometry gt From File . . . and browse
    to the file Axisym_pressure_3D.x_t.

22
Workshop 4.2 Preprocessing
  • The working unit system should still be set to
    the metric mm system.
  • Units gt Metric (mm, Kg, MPa, C, s).
  • Note, once again rename the 2 parts in the model
    Retaining Ring and Pressure Cap

23
Workshop 4.2 Preprocessing
  • From details for the Pressure Cap and import
    the material Stainless Steel.

2
24
Workshop 4.2 Contact
  • Highlight the Contact Region branch and change
    the Type to Frictionless.
  • Highlight the Mesh branch, RMB and Preview
    Mesh.
  • Refer to p. 4.1-11 to compare the 2D mesh.

3
4
25
Workshop 4.2 Environment
  1. From the Environment branch highlight the 6 faces
    representing the planes of symmetry (cut planes).
  2. RMB gt Insert gt Frictionless Support.

6
5
Note there are six (6) faces to select.
Note, frictionless supports provide constraints
in the normal direction. This is used to model
the symmetry condition.
26
Workshop 4.2 Environment
  1. Highlight the bottom face of the pressure cap,
    RMB gt Insert gt Compression Only Support.

27
Workshop 4.2 Environment
  1. Highlight the 3 inside faces on the pressure cap,
    RMB gt Insert gt Pressure.

8
  1. Change the Magnitude to 0.1 in the detail
    window.

28
Workshop 4.2 Environment
  1. Highlight the 3 cylindrical faces of the bolt
    holes, RMB gt Insert gt Fixed Support.

29
Workshop 4.2 Solution
  • Highlight the Solution branch, RMB and insert
  • Stress gt Equivalent (von-Mises)
  • Deformation gt Total
  • Switch to body select mode, select the pressure
    cap and repeat steps 16 and 17.
  • Solve

13
As before, the last two results are scoped to the
pressure cap.
30
Workshop 4.2 Postprocessing
  • As before highlight each of the result objects
    and inspect the response.
  • For reference, highlight the Equivalent Stress
    2 result (scoped) and note the maximum value
    here________________

31
Workshop 4.2 Postprocessing
  • Highlight the Solution branch, RMB gt Insert gt
    Solution Information gt Solution Information.

The graphics window will change to the Worksheet
view. Scroll to the bottom of the solution
information and note the Elapsed Time (this will
vary by machine). Elapsed Time
___________________________
32
Workshop 4.2 Comparison
  • Using the example shown in the exercise we now
    compare analyses (note, your actual results may
    vary from those shown here. Also, your solution
    times will almost certainly differ from those
    shown here.
  • Maximum von-Mises Stress Results
  • Axisymmetric 0.840 MPa
  • 3D Symmetry 0.735 MPa
  • Note, meshing differences account for the results
    difference (see next page). Recall that the 2D
    model resulted in a more refined mesh than the
    3D. The next page shows the results from a more
    refined 3D model.
  • Elapsed Time
  • Axisymmetric 7.0 seconds
  • 3D Symmetry 46.0 seconds

33
Workshop 4.2 Comparison
  • Maximum von-Mises Stress Results
  • 3D Symmetry (refined) 0.852 MPa
  • Elapsed Time
  • 3D Symmetry (refined) 578.0 seconds

Results using a more refined mesh with the 3D
symmetry model
34
(No Transcript)
Write a Comment
User Comments (0)
About PowerShow.com